I am trying to get cutviewer to work by using the option in the tools menu but a message appears that says
"The system cannot find the file specified". which file does this refer to
Does the link work and if so what do i need to do to get it operating.
The CutViewer link requires that CutViewer Mill is installed, available from here:
http://www.cutviewer.com/They provide a 30 day free evaluation. The CamBam shop sells a combined CamBam and CutViewer Mill licence. If you have already purchased a CamBam licence and would like to buy a CutViewer licence, please PM me or use the contact page
http://www.cambam.co.uk/contact.htmlTo work better with CutViewer, CamBam needs to output CutViewer specific comments in the g-code output. This can be done by using the following Machining custom file header:
(FROM/{start x},{start y},{start z})
(TOOL/MILL,{tool diameter},{tool corner radius},{tool height},{tool taper})
(STOCK/BLOCK,{length},{width},{height},{origin x},{origin y},{origin z} )
NOTE: replace the values in {} braces with your numerical values.
The initial tool definition can be anything and is to prevent tool setup messages before any moves.
Then for each machining operation, you can add a custom mop header:
(TOOL/MILL,$t,0,{tool height},0)
NOTE: the $t macro will be automatically replaced with the current tool diameter when the gcode is generated.
Examples:
(FROM/0,0,5)
(TOOL/MILL,6,0,20.0,0)
(STOCK/BLOCK,76.20,215.0,12.7,76.2,2.5,12.7 )
(TOOL/MILL,$t,0,20.0,0)
There are some problems where tool changes occur after preparatory moves. This will be resolved when the new post processor system is in place.
I hope this helps.